/*! \file writeOpenFOAM15x.cpp
*  \brief Export Netgen Mesh in the OpenFOAM 1.5+ File format
*  \author Philippose Rajan
*  \date 25 October 2009
*
*  This function extends the export capabilities of
*  Netgen to include the OpenFOAM 1.5+ File Format.
*
*  The OpenFOAM 1.5+ mesh format consists of a set of 5 files 
*  which together define the mesh points, faces, cells and 
*  boundary conditions. 
*
*  The files are:
*  1. points    -> A list of the point co-ordinates
*  2. faces     -> A list of the faces with format <n>(pnt_ind1 pnt_ind2 .... pnt_ind<n>)
*  3. owner     -> The owner cell of each face 
*  4. neighbour -> The neighbour cell of each face
*  5. boundary  -> The set of boundaries with name, start face, and num. of faces
*
*  For a detailed description of the format, refer to the following link:
*  http://openfoamwiki.net/index.php/Write_OpenFOAM_meshes
*
*/

#include <mystdlib.h>

#include <myadt.hpp>
#include <linalg.hpp>
#include <csg.hpp>
#include <meshing.hpp>
#include <sys/stat.h>


namespace netgen
{
#include "writeuser.hpp"

   // Global arrays used to maintain the owner, neighbour and face lists 
   // so that they are accessible across functions
   static Array<int> owner_facelist;
   static Array<int> owner_celllist;
   static Array<int> neighbour_celllist;
   static Array<int> surfelem_bclist;
   static Array<INDEX_2> surfelem_lists;



   static void WriteOpenFOAM15xBanner(ofstream & outfile)
   {
      static char FOAMversion[4] = "1.5";
      static char spaces[40];

      memset(spaces, ' ', 40);
      spaces[38 - strlen(FOAMversion)] = '\0';
      
      outfile << 
              "/*--------------------------------*- C++ -*----------------------------------*\\\n";

      outfile <<
              "| =========                 |                                                 |\n"
              "| \\\\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox           |\n"
              "|  \\\\    /   O peration     | Version:  " << FOAMversion << spaces << "|\n"
              "|   \\\\  /    A nd           | Web:      http://www.OpenFOAM.org               |\n"
              "|    \\\\/     M anipulation  |                                                 |\n"
              "\\*---------------------------------------------------------------------------*/\n";

   }



   static void WriteOpenFOAM15xDividerStart(ofstream & outfile)
   {
      outfile  <<
               "// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //\n";
   }



   static void WriteOpenFOAM15xDividerEnd(ofstream & outfile)
   {
      outfile <<
              "// ************************************************************************* //\n";
   }



   static bool BuildOwnerNeighbourLists (const Mesh & mesh)
   {
      // Clear all the arrays
      owner_facelist.DeleteAll();
      owner_celllist.DeleteAll();
      neighbour_celllist.DeleteAll();
      surfelem_bclist.DeleteAll();
      surfelem_lists.DeleteAll();

      const MeshTopology& meshtopo = mesh.GetTopology();
      
      // Update the mesh topology structures
      const_cast<MeshTopology&> (meshtopo).SetBuildEdges(true);
      const_cast<MeshTopology&> (meshtopo).SetBuildFaces(true);
      const_cast<MeshTopology&> (meshtopo).Update();

      // Extract important mesh metrics
      int ne = mesh.GetNE();
      int nse = mesh.GetNSE();
      int totfaces = meshtopo.GetNFaces();

      // Preset the size of the arrays to speed up future operations
      // Number of internal faces = total faces - num. of surface faces
      owner_facelist.SetSize(totfaces - nse);
      owner_celllist.SetSize(totfaces - nse);
      neighbour_celllist.SetSize(totfaces - nse);
      surfelem_bclist.SetSize(nse);
      surfelem_lists.SetSize(nse);

      // Initialise arrays to zero if required
      neighbour_celllist = 0;

      // Array used to keep track of Faces which have already been 
      // processed and added to the Owner list... In addition, also the 
      // location where the face appears in the Owner list is also stored 
      // to speed up creation of the Neighbour list
      Array<int> ownerfaces(totfaces);
      ownerfaces = 0;

      // Array to hold the set of local faces of each volume element 
      // while running through the set of volume elements
      // NOTE: The size is set automatically by the Netgen topology function
      Array<int> locfaces;

      // Secondary indices used to independently advance the owner 
      // and boundary condition arrays within the main loop
      int owner_ind = 1;
      int bc_ind = 1;

      // Loop through all the volume elements
      for(int elind = 1; elind <= ne; elind++)
      {
         // Extract the current volume element
         const Element & el = mesh.VolumeElement(elind);

         // Get the face numbers of the faces of the current volume element
         // The values returned are given a sign depending on the orientation 
         // of the faces. This is used while writing the faces file, to 
         // determine whether or not to invert the face triangle before writing 
         // it to file
         meshtopo.GetElementFaces(elind,locfaces,true);

         // Loop through the faces
         for(int i = 1; i <= locfaces.Size(); i++)
         {
            // The absolute value of a face number (because the faces 
            // returned by the GetElementFaces function prepend it 
            // with a sign depending on the face orientation)
            int absfacenr = abs(locfaces.Elem(i));

            // If the face already exists in the owner list, add 
            // the current cell into the neighbour list, in the 
            // same location where the face appears in the owner list
            int owner_face = ownerfaces.Elem(absfacenr);
            if(owner_face)
            {
               neighbour_celllist.Elem(owner_face) = elind;

               // From this point on, the code within this "if" block 
               // basically sorts the order of the the Neighbour cells (along 
               // with the faces list) in ascending order.
               // The approach used is..... to traverse the owner and neighbour cell lists
               // up and down, and sort the neighbour cells of a given owner cell 
               // as the list evolves.
               // NOTE: A value of "zero" in the neighbour list implies that 
               // the neighbour has not been found yet, so the "zero" locations need 
               // to be skipped while sorting in ascending order
               int curr_owner = owner_celllist.Elem(owner_face);

               int peek_loc = owner_face - 1;
               int new_loc = owner_face;

               // Traversing upwards in the list
               while((owner_celllist.Elem(peek_loc) == curr_owner) && (peek_loc >= 1))
               {
                  if((neighbour_celllist.Elem(peek_loc) != 0) 
                     && (neighbour_celllist.Elem(new_loc) < neighbour_celllist.Elem(peek_loc)))
                  {
                     Swap(neighbour_celllist.Elem(new_loc),neighbour_celllist.Elem(peek_loc));
                     Swap(owner_facelist.Elem(new_loc),owner_facelist.Elem(peek_loc));
                     new_loc = peek_loc;
                  }

                  peek_loc--;
               }

               peek_loc = owner_face + 1;

               // Traversing downwards in the list
               while((owner_celllist.Elem(peek_loc) == curr_owner) && (peek_loc <= owner_ind))
               {
                  if((neighbour_celllist.Elem(peek_loc) != 0) 
                     && (neighbour_celllist.Elem(new_loc) > neighbour_celllist.Elem(peek_loc)))
                  {
                     Swap(neighbour_celllist.Elem(new_loc),neighbour_celllist.Elem(peek_loc));
                     Swap(owner_facelist.Elem(new_loc),owner_facelist.Elem(peek_loc));
                     new_loc = peek_loc;
                  }

                  peek_loc++;
               }

               continue;
            }

            // Check if the face is a surface element (boundary face)
            // if not, add the current volume element and the corresponding face into 
            // the owner list
            int surfelem = meshtopo.GetFace2SurfaceElement(absfacenr);
            if(!surfelem)
            {
               // If it is a new face which has not been listed before, 
               // add the current cell into the owner list, and save 
               // the index location to be used later by the neighbour list
               owner_celllist.Elem(owner_ind) = elind;
               owner_facelist.Elem(owner_ind) = locfaces.Elem(i);
               // Update the array to indicate that the face is already processed
               ownerfaces.Elem(absfacenr) = owner_ind;

               owner_ind++;
            }
            // If the face is a boundary face, extract the boundary condition number of the 
            // face, and append that along with the face number and the current cell 
            // into the various surface elements lists
            else
            {
               Element2d sel = mesh.SurfaceElement(surfelem);
               surfelem_bclist.Elem(bc_ind) = mesh.GetFaceDescriptor(sel.GetIndex()).BCProperty();
               surfelem_lists.Elem(bc_ind) = INDEX_2(locfaces.Elem(i),elind);

               bc_ind++;
            }
         }
      }

      // This correction is required in cases where the mesh has been "uniform refined".... for 
      // some reason, the number of faces reported by Netgen is higher than the actual number 
      // of faces in the mesh
      owner_facelist.SetSize(owner_ind-1);
      owner_celllist.SetSize(owner_ind-1);
      neighbour_celllist.SetSize(owner_ind-1);


      // Sort the list of surface elements in ascending order of boundary condition number
      // also sort the cell list in the same manner
      QuickSort(surfelem_bclist,surfelem_lists);

/*    
      // Debugging output to a file 
      ofstream dbg("OpenFOAMDebug.log");

      dbg << " ------- Boundary List -------- \n";

      for(int i = 1; i <= surfelem_bclist.Size(); i++)
      {
         dbg << "bc = " << surfelem_bclist.Elem(i) 
              << " : face = " << surfelem_lists.Elem(i).I1()
              << " : cell = " << surfelem_lists.Elem(i).I2() << "\n";
      }

      dbg << "\n ------- Owner / Face / Neighbour List ------- \n";

      for(int i = 1; i <= owner_celllist.Size(); i++)
      {
         dbg << "Ind:" << i << " :: (" 
              << owner_celllist.Elem(i) << " "
              << owner_facelist.Elem(i) << "  "
              << neighbour_celllist.Elem(i) << ")\n";
      }

      dbg.close();
*/
      return(false);
   }



   static void WriteNeighbourFile (ofstream & outfile)
   {
      // Write the OpenFOAM standard banner and dividers, etc...
      WriteOpenFOAM15xBanner(outfile);
      outfile << "FoamFile \n"
              << "{ \n"
              << "    version     2.0; \n"
              << "    format      ascii; \n"
              << "    class       labelList; \n"
              << "    note        \"Mesh generated and converted using NETGEN-" << PACKAGE_VERSION << "\"; \n"
              << "    location    \"constant\\polyMesh\"; \n"
              << "    object      neighbour; \n"
              << "} \n";
      WriteOpenFOAM15xDividerStart(outfile);

      outfile << "\n\n";

      int nneighbours = neighbour_celllist.Size();

      outfile << nneighbours << "\n";

      outfile << "(\n";

      // Write the neighbour cells to file
      for(int i = 1; i <= neighbour_celllist.Size(); i++)
      {
         outfile << neighbour_celllist.Elem(i) - 1 << "\n";
      }
      outfile << ")\n\n";
      WriteOpenFOAM15xDividerEnd(outfile);
   }



   static void WriteOwnerFile (ofstream & outfile)
   {
      // Write the OpenFOAM standard banner and dividers, etc...
      WriteOpenFOAM15xBanner(outfile);
      outfile << "FoamFile \n"
              << "{ \n"
              << "    version     2.0; \n"
              << "    format      ascii; \n"
              << "    class       labelList; \n"
              << "    note        \"Mesh generated and converted using NETGEN-" << PACKAGE_VERSION << "\"; \n"
              << "    location    \"constant\\polyMesh\"; \n"
              << "    object      owner; \n"
              << "} \n";
      WriteOpenFOAM15xDividerStart(outfile);

      outfile << "\n\n";

      int nowners = owner_celllist.Size() + surfelem_lists.Size();

      outfile << nowners << "\n";

      outfile << "(\n";

      // Write the owners of the internal cells to file
      for(int i = 1; i <= owner_celllist.Size(); i++)
      {
         outfile << owner_celllist.Elem(i) - 1 << "\n";
      }

      // Write the owners of the boundary cells to file
      // (Written in order of ascending boundary condition numbers)
      for(int i = 1; i <= surfelem_lists.Size(); i++)
      {
         outfile << surfelem_lists.Elem(i).I2() - 1 << "\n";
      }
      outfile << ")\n\n";
      WriteOpenFOAM15xDividerEnd(outfile);
   }



   static void WriteFacesFile (ofstream & outfile, const Mesh & mesh)
   {
      const MeshTopology& meshtopo = mesh.GetTopology();

      // Write the OpenFOAM standard banner and dividers, etc...
      WriteOpenFOAM15xBanner(outfile);
      outfile << "FoamFile \n"
              << "{ \n"
              << "    version     2.0; \n"
              << "    format      ascii; \n"
              << "    class       faceList; \n"
              << "    note        \"Mesh generated and converted using NETGEN-" << PACKAGE_VERSION << "\"; \n"
              << "    location    \"constant\\polyMesh\"; \n"
              << "    object      faces; \n"
              << "} \n";
      WriteOpenFOAM15xDividerStart(outfile);

      outfile << "\n\n";

      int nfaces = owner_facelist.Size() + surfelem_lists.Size();

      outfile << nfaces << "\n";

      outfile << "(\n";

      // Array to hold the indices of the points of each face to 
      // flip if required 
      Array<int> facepnts;

      // Write the faces in the order specified in the owners lists of the 
      // internal cells and the boundary cells
      for(int i = 1; i <= owner_facelist.Size(); i++)
      {
         int face_w_orientation = owner_facelist.Elem(i);
         int facenr = abs(face_w_orientation);

         meshtopo.GetFaceVertices(facenr,facepnts);

         // Get the orientation of the face, and invert it if required
         // Since the faces already have the orientation "embedded" into 
         // them by means of the prepended sign, only this needs to be 
         // checked for...
         if(face_w_orientation > 0)
         {
            int tmppnts = 0;

            if(facepnts.Size() == 4)
            {
               tmppnts = facepnts.Elem(1);
               facepnts.Elem(1) = facepnts.Elem(2);
               facepnts.Elem(2) = tmppnts;
               
               tmppnts = facepnts.Elem(3);
               facepnts.Elem(3) = facepnts.Elem(4);
               facepnts.Elem(4) = tmppnts;
            }
            else if(facepnts.Size() == 3)
            {
               tmppnts = facepnts.Elem(1);
               facepnts.Elem(1) = facepnts.Elem(3);
               facepnts.Elem(3) = tmppnts;
            }
         }

         outfile << facepnts.Size();
         outfile << "(";
         for(int j = 1; j <= facepnts.Size(); j++)
         {
            outfile << facepnts.Elem(j)-1;
            if(j != facepnts.Size()) outfile << " ";
         }
         outfile << ")\n";
      }

      // Now append the faces of the surface elements (written in 
      // ascending order of boundary condition number) also into 
      // the faces file
      for(int i = 1; i <= surfelem_lists.Size(); i++)
      {
         int face_w_orientation = surfelem_lists.Elem(i).I1();
         int facenr = abs(face_w_orientation);

         meshtopo.GetFaceVertices(facenr,facepnts);

         // Get the orientation of the face, and invert it if required
         if(face_w_orientation > 0)
         {
            int tmppnts = 0;

            if(facepnts.Size() == 4)
            {
               tmppnts = facepnts.Elem(1);
               facepnts.Elem(1) = facepnts.Elem(2);
               facepnts.Elem(2) = tmppnts;
               
               tmppnts = facepnts.Elem(3);
               facepnts.Elem(3) = facepnts.Elem(4);
               facepnts.Elem(4) = tmppnts;
            }
            else if(facepnts.Size() == 3)
            {
               tmppnts = facepnts.Elem(1);
               facepnts.Elem(1) = facepnts.Elem(3);
               facepnts.Elem(3) = tmppnts;
            }
         }

         outfile << facepnts.Size();
         outfile << "(";
         for(int j = 1; j <= facepnts.Size(); j++)
         {
            outfile << facepnts.Elem(j)-1;
            if(j != facepnts.Size()) outfile << " ";
         }
         outfile << ")\n";
      }

      outfile << ")\n\n";
      WriteOpenFOAM15xDividerEnd(outfile);
   }


 
   static void WritePointsFile (ofstream & outfile, const Mesh & mesh)
   {
      int np = mesh.GetNP();

      // Write the OpenFOAM standard banner and dividers, etc...
      WriteOpenFOAM15xBanner(outfile);
      outfile << "FoamFile \n"
              << "{ \n"
              << "    version     2.0; \n"
              << "    format      ascii; \n"
              << "    class       vectorField; \n"
              << "    note        \"Mesh generated and converted using NETGEN-" << PACKAGE_VERSION << "\"; \n"
              << "    location    \"constant\\polyMesh\"; \n"
              << "    object      points; \n"
              << "} \n";
      WriteOpenFOAM15xDividerStart(outfile);

      outfile << "\n\n";

      // Number of points in the following list
      outfile << np << "\n";

      outfile.precision(6);
      outfile.setf (ios::fixed, ios::floatfield);
      outfile.setf (ios::showpoint);

      // Coordinate list starts here
      outfile << "(\n";

      for(int i = 1; i <= np; i++)
      {
         const Point3d & p = mesh.Point(i);

         // Write coordinates to file
         outfile << "(";
         outfile << p.X() << " ";
         outfile << p.Y() << " ";
         outfile << p.Z();
         outfile << ")\n";
      }
      outfile << ")\n\n";
      WriteOpenFOAM15xDividerEnd(outfile);
   }



   static void WriteBoundaryFile (ofstream & outfile)
   {
      // Write the OpenFOAM standard banner and dividers, etc...
      WriteOpenFOAM15xBanner(outfile);
      outfile << "FoamFile \n"
              << "{ \n"
              << "    version     2.0; \n"
              << "    format      ascii; \n"
              << "    class       polyBoundaryMesh; \n"
              << "    note        \"Mesh generated and converted using NETGEN-" << PACKAGE_VERSION << "\"; \n"
              << "    location    \"constant\\polyMesh\"; \n"
              << "    object      boundary; \n"
              << "} \n";
      WriteOpenFOAM15xDividerStart(outfile);

      outfile << "\n";


      Array<INDEX_3> bcarray;
      int ind = 1;

      // Since the boundary conditions are already sorted in ascending 
      // order, the last element will give the maximum number of possible 
      // boundary condition entries
      int bcmax = surfelem_bclist.Elem(surfelem_bclist.Size());

      bcarray.SetSize(bcmax+1);

      bcarray.Elem(ind) = INDEX_3(surfelem_bclist.Elem(1),1,0);
            
      for(int i = 2; i <= surfelem_bclist.Size(); i++)
      {
         if(surfelem_bclist.Elem(i) == bcarray.Elem(ind).I1())
         {
            bcarray.Elem(ind).I2() = bcarray.Elem(ind).I2()+1;
         }
         else
         {
            ind++;
            bcarray.Elem(ind) = INDEX_3(surfelem_bclist.Elem(i),1,i-1);
         }
      }

      bcarray.SetSize(ind);

      outfile << bcarray.Size() << "\n";
      outfile << "(\n";

      int startface = 0;

      for(int i = 1; i <= bcarray.Size(); i++)
      {
         startface = owner_celllist.Size() + bcarray.Elem(i).I3();

         outfile << "    patch" << bcarray.Elem(i).I1() << "\n"
                 << "    {\n"
                 << "        type            patch;\n"
                 << "        physicalType    patch;\n"
                 << "        nFaces          " << bcarray.Elem(i).I2() << ";\n"
                 << "        startFace       " << startface << ";\n"
                 << "    }\n";
      }

      outfile << ")\n\n";
      WriteOpenFOAM15xDividerEnd(outfile);
   }



   void WriteOpenFOAM15xFormat (const Mesh & mesh, const string & casename)
   {
      int i,j;
      bool error = false;
      char casefiles[256];

      // Make sure that the mesh data has been updated
      const_cast<Mesh&> (mesh).Compress();
      const_cast<Mesh&> (mesh).CalcSurfacesOfNode();
      const_cast<Mesh&> (mesh).RebuildSurfaceElementLists();
      const_cast<Mesh&> (mesh).BuildElementSearchTree();


      int np = mesh.GetNP();
      int nse = mesh.GetNSE();
      int ne = mesh.GetNE();

      cout << "Write OpenFOAM 1.5+ Mesh Files....\n";

      // Abort if there are no points, surface elements or volume elements
      if((np <= 0) || (ne <= 0) || (nse <= 0))
      {
         cout << "Export Error: Invalid mesh.... Aborting!\n";
         return;
      }

      // OpenFOAM only supports linear meshes!
      if(mparam.secondorder || mesh.GetCurvedElements().IsHighOrder())
      {
         cout << "Export Error: OpenFOAM 1.5+ does not support non-linear elements.... Aborting!\n";
         return;
      }

      if((mesh.SurfaceElement(nse/2).GetType() != TRIG) 
         && (mesh.SurfaceElement(nse/2).GetType() != QUAD)
         || (mesh.VolumeElement(ne/2).GetType() == TET10)
         || (mesh.VolumeElement(ne/2).GetType() == PRISM12))
      {
         cout << "Export Error: OpenFOAM 1.5+ does not support non-linear elements.... Aborting!\n";
         return;
      }


      cout << "Writing OpenFOAM 1.5+ Mesh files to case: " << casename << "\n";

      // Create the case directory if it does not already exist
      // NOTE: This needs to be improved for the Linux variant....!!!
   #ifdef WIN32
      char casedir[256];
      sprintf(casedir, "mkdir %s\\constant\\polyMesh", casename.c_str());
      system(casedir);
   #else
      char casedir[256];
      mkdir(casename.c_str(), S_IRWXU|S_IRWXG);
      sprintf(casedir, "%s/constant", casename.c_str());
      mkdir(casedir, S_IRWXU|S_IRWXG);
      sprintf(casedir, "%s/constant/polyMesh", casename.c_str());
      mkdir(casedir, S_IRWXU|S_IRWXG);
   #endif

      // Open handles to the five required mesh files
      // points
      // faces
      // owner
      // neighbour
      // boundary
      sprintf(casefiles, "%s/constant/polyMesh/points", casename.c_str());
      ofstream outfile_pnts(casefiles);
      sprintf(casefiles, "%s/constant/polyMesh/faces", casename.c_str()); 
      ofstream outfile_faces(casefiles);
      sprintf(casefiles, "%s/constant/polyMesh/owner", casename.c_str()); 
      ofstream outfile_own(casefiles);
      sprintf(casefiles, "%s/constant/polyMesh/neighbour", casename.c_str()); 
      ofstream outfile_nei(casefiles);
      sprintf(casefiles, "%s/constant/polyMesh/boundary", casename.c_str()); 
      ofstream outfile_bnd(casefiles);

      ResetTime();

      // Build the owner, neighbour, faces and boundary lists 
      // from the Netgen mesh
      cout << "\nBuilding Owner, Neighbour and Face Lists: ";

      error = BuildOwnerNeighbourLists(mesh);

      cout << "Done! (Time Elapsed = " << GetTime() << " sec)\n";


      // Write the "owner" file
      if(outfile_own.good() && !error)
      {
         cout << "Writing the owner file: ";
         WriteOwnerFile(outfile_own);
         outfile_own.close();
         cout << "Done! (Time Elapsed = " << GetTime() << " sec)\n";
      }
      else
      {
         cout << "Export Error: Error creating file: owner.... Aborting\n";
         error = true;
      }


      // Write the "neighbour" file
      if(outfile_nei.good() && !error)
      {
         cout << "Writing the neighbour file: ";
         WriteNeighbourFile(outfile_nei);
         outfile_nei.close();
         cout << "Done! (Time Elapsed = " << GetTime() << " sec)\n";
      }
      else
      {
         cout << "Export Error: Error creating file: neighbour.... Aborting\n";
         error = true;
      }


      // Write the "faces" file
      if(outfile_faces.good() && !error)
      {
         cout << "Writing the faces file: ";
         WriteFacesFile(outfile_faces, mesh);
         outfile_faces.close();
         cout << "Done! (Time Elapsed = " << GetTime() << " sec)\n";
      }
      else
      {
         cout << "Export Error: Error creating file: faces.... Aborting\n";
         error = true;
      }


      // Write the "points" file
      if(outfile_pnts.good() && !error)
      {
         cout << "Writing the points file: ";
         WritePointsFile(outfile_pnts,mesh);
         outfile_pnts.close();
         cout << "Done! (Time Elapsed = " << GetTime() << " sec)\n";
      }
      else
      {
         cout << "Export Error: Error creating file: points.... Aborting\n";
         error = true;
      }


      // Write the "boundary" file
      if(outfile_bnd.good() && !error)
      {
         cout << "Writing the boundary file: ";
         WriteBoundaryFile(outfile_bnd);
         outfile_bnd.close();
         cout << "Done! (Time Elapsed = " << GetTime() << " sec)\n";
      }
      else
      {
         cout << "Export Error: Error creating file: boundary.... Aborting\n";
         error = true;
      }

      if(!error)
      {
         cout << "OpenFOAM 1.5+ Export successfully completed (Time elapsed = " << GetTime() << " sec) !\n";
      }
      else
      {
         cout << "Error in OpenFOAM 1.5+ Export.... Aborted!\n";
      }
   }
}